X-Authentication-Warning:	delorie.com: mail set sender to geda-user-bounces using -f
X-Recipient:	geda-user AT delorie DOT com
Date:	Tue, 14 Jan 2014 10:14:13 +0100
From:	Jan Kasprzak <kas AT fi DOT muni DOT cz>
To:	geda-user AT delorie DOT com
Subject:	Re: [geda-user] Side-mounted header connector
Message-ID:	<20140114091413.GH18632@fi.muni.cz>
References:	<20140114072906 DOT GE18632 AT fi DOT muni DOT cz>
	<20140114080501 DOT 5CE2E8045B75 AT turkos DOT aspodata DOT se>
MIME-Version:	1.0
In-Reply-To:	<20140114080501.5CE2E8045B75@turkos.aspodata.se>
User-Agent:	Mutt/1.5.20 (2009-12-10)
X-Muni-Spam-TestIP:	147.251.48.3
X-Greylist:	Sender IP whitelisted, not delayed by milter-greylist-4.3.7 (tirith.ics.muni.cz [147.251.4.35]); Tue, 14 Jan 2014 10:14:15 +0100 (CET)
X-Virus-Scanned:	clamav-milter 0.97.8 at tirith.ics.muni.cz
X-Virus-Status:	Clean
Reply-To:	geda-user AT delorie DOT com
Errors-To:	nobody AT delorie DOT com
X-Mailing-List:	geda-user AT delorie DOT com
X-Unsubscribes-To:	listserv AT delorie DOT com

--tT3UgwmDxwvOMqfu
Content-Type: text/plain; charset=us-ascii
Content-Disposition: inline

karl AT aspodata DOT se wrote:
: Yenya:
: > I would like to use a 2x3 pin, 2.54mm spaced header connector for in-system
: > programming of the MCU, but I am pretty restricted in the vertical direction.
: > So I considered a side-mounted connector: one row of pins on the top side
: > of the PCB, and another row on the bottom side, similar to the header
: > on the right side of the following image:
: > 
: > http://fabiobaltieri.files.wordpress.com/2011/08/usbasp.jpg?w=630
: > 
: > Is it possible to describe it with a single footprint?
: 
: Yes, use a pad on each side like in
: 
: http://turkos.aspodata.se/git/openhw/share/pcb/_connector/wascator_edge_3.fp
: 
:    Pad[ 10mm -3mm  10mm 3mm  2.0mm 0.5mm 0.2mm "1" "1" "square" ]
:    Pad[ 10mm -3mm  10mm 3mm  2.0mm 0.5mm 0.2mm "1" "1" "square,onsolder" ]
: 
	That's it, thanks!

	FWIW, here is the 2x3 edge-mounted header, I will also add it
to gedasymbols.org.

	BTW, is there any way to make also silk layer lines "onsolder"?
Thanks,

-Yenya

-- 
| Jan "Yenya" Kasprzak  <kas at {fi.muni.cz - work | yenya.net - private}> |
| New GPG 4096R/A45477D5 - see http://www.fi.muni.cz/~kas/pgp-rollover.txt |
| http://www.fi.muni.cz/~kas/    Journal: http://www.fi.muni.cz/~kas/blog/ |
Please don't top post and in particular don't attach entire digests to your
mail or we'll all soon be using bittorrent to read the list.     --Alan Cox

--tT3UgwmDxwvOMqfu
Content-Type: text/plain; charset=us-ascii
Content-Disposition: attachment; filename="header3_2_edge.fp"

Element["Header 3x2, 2.54mm, edge-mounted" "header3_2_edge" "X?" "" 0 0 -12500  5000 0 100 ""]
(
   Pad[     0  -7500     0 7500 5000 2000 6000 "1" "1" "square" ]
   Pad[     0  -7500     0 7500 5000 2000 6000 "2" "2" "square,onsolder" ]

   Pad[ 10000  -7500 10000 7500 5000 2000 6000 "3" "3" "square" ]
   Pad[ 10000  -7500 10000 7500 5000 2000 6000 "4" "4" "square,onsolder" ]

   Pad[ 20000  -7500 20000 7500 5000 2000 6000 "5" "5" "square" ]
   Pad[ 20000  -7500 20000 7500 5000 2000 6000 "6" "6" "square,onsolder" ]

   ElementLine[  -5000 -8500  -5000 11000 1000 ]
   ElementLine[  25000 -8500  25000 11000 1000 ]
   ElementLine[  -5000 11000  25000 11000 1000 ]

   ElementLine[  -3750     0  -5000     0 1000 ]
   ElementLine[  -3750     0  -3750 11000 1000 ]
   Attribute("author" "Jan Yenya Kasprzak, http://www.fi.muni.cz/~kas/")
   Attribute("copyright" "Jan Yenya Kasprzak, http://www.fi.muni.cz/~kas/")
   Attribute("use-license" "Unlimited")
   Attribute("dist-license" "GPL 2.0")
   Attribute("comment" "Thanks: Karl Hammar")
)

--tT3UgwmDxwvOMqfu--

- Raw text -