delorie.com/archives/browse.cgi | search |
X-Authentication-Warning: | delorie.com: mail set sender to geda-user-bounces using -f |
X-Recipient: | geda-user AT delorie DOT com |
Date: | Thu, 19 Jul 2012 16:00:03 -0700 |
From: | Colin D Bennett <colin AT gibibit DOT com> |
To: | geda-user AT delorie DOT com |
Subject: | [geda-user] pcb footprint update hack |
Message-ID: | <20120719160003.3a3fb538@svelte> |
In-Reply-To: | <201207191846.q6JIkbTb030133@envy.delorie.com> |
References: | <20120719182728 DOT GA12447 AT slana DOT eecs DOT oregonstate DOT edu> |
<201207191846 DOT q6JIkbTb030133 AT envy DOT delorie DOT com> | |
X-Mailer: | Claws Mail 3.8.0 (GTK+ 2.24.10; x86_64-pc-linux-gnu) |
Mime-Version: | 1.0 |
X-AntiAbuse: | This header was added to track abuse, please include it with any abuse report |
X-AntiAbuse: | Primary Hostname - gator297.hostgator.com |
X-AntiAbuse: | Original Domain - delorie.com |
X-AntiAbuse: | Originator/Caller UID/GID - [47 12] / [47 12] |
X-AntiAbuse: | Sender Address Domain - gibibit.com |
X-BWhitelist: | no |
X-Source: | |
X-Source-Args: | |
X-Source-Dir: | |
X-Source-Sender: | (svelte) [67.160.113.82]:42006 |
X-Source-Auth: | colin AT gibibit DOT com |
X-Email-Count: | 1 |
X-Source-Cap: | c2t5bGVuO3NreWxlbjtnYXRvcjI5Ny5ob3N0Z2F0b3IuY29t |
Reply-To: | geda-user AT delorie DOT com |
Errors-To: | nobody AT delorie DOT com |
X-Mailing-List: | geda-user AT delorie DOT com |
X-Unsubscribes-To: | listserv AT delorie DOT com |
On Thu, 19 Jul 2012 14:46:37 -0400 DJ Delorie <dj AT delorie DOT com> wrote: > > So, what is the proper procedure? > > View->Displayed Element Name->Description > > that's the "footprint name" that the importer knows about. > > Change it to anything different (i.e. delete a char or append > "x"), and it will do a footprint update, at least pcb's > File->Import will. I thing gnetlist will replace the footprint, > but not keep it in the same place. > > You should try out pcb's File->Import if your version has it, it's > much better at live and in-place updates that gsch2pcb. Yes, definitely use the Import Schematics feature of pcb (File | Import Schematics menu item or the ":Import()" command). You can set attributes on the board to tell pcb to read multiple schematic files, like: Attribute("import::src0" "../Schematic/Connectors_and_Power.sch") Attribute("import::src1" "../Schematic/Microcontroller.sch") Attribute("import::src2" "../Schematic/Radio.sch") and define footprint library path by putting a text file called pcb.settings in your layout file directory, with the following content: lib-newlib = ../Footprints Now for the hack which allows you to easily get a footprint updated in pcb when you edit the footprint file in your library. It would be great to get this integrated into pcb, but for now this is ten times better than any other way, especially when you have multiple instances of a footprint in your schematic. ---------------------------------------------------------------- How to get pcb to update footprints in a layout when the footprint file in the library on disk has been updated: Suppose you have the following set of files for your project, for simplicity's sake: Board.pcb Schematic.sch XYZ123.fp Suppose further that you have 50 instances of XYZ123 on your schematic. You really don't want to do this manually. 1. Rename the old footprint file to a different name: mv XYZ123.fp XYZ123_old.fp This is necessary to get pcb to re-import the footprint. 2. Replace all instances of this in your schematic with the temporary name: sed -i -e 's/footprint=XYZ123/footprint=XYZ123_old/' 3. Open the layout in pcb and update the layout from schematic. pcb Board.pcb Execute File | Import Schematics. 4. Save the layout. 5. Put the new footprint file in place under the original name (XYZ123.fp). You can delete the XYZ123_old.fp file now. 6. Fix your schematic back to the proper name: sed -i -e 's/footprint=XYZ123_old/footprint=XYZ123/' (or, you could "bzr revert Schematic.sch" if you have it version controlled and have no other changes -- much faster if you are updating multiple different footprint files) 7. Open the layout in pcb and update the layout from schematic. pcb Board.pcb Execute File | Import Schematics. 8. You might have to fix some components, they sometimes are rotated incorrectly after being updated. Use the rotate tool and click on the component reference point (diamond) until things are lined up. 9. Save the layout. 10. Sit back and relax. Think about how nice it would be if it were automated and seamless. :-) Regards, Colin
webmaster | delorie software privacy |
Copyright © 2019 by DJ Delorie | Updated Jul 2019 |