X-Authentication-Warning:	delorie.com: mail set sender to geda-user-bounces using -f
X-Recipient:	geda-user AT delorie DOT com
X-Virus-Scanned:	amavisd-new at oregonstate.edu
Date:	Tue, 29 May 2012 17:45:36 -0700
From:	Traylor Roger <traylor AT eecs DOT oregonstate DOT edu>
To:	geda-user AT delorie DOT com
Cc:	Russ DOT Dill AT asu DOT edu
Subject:	Re: [geda-user] rectangular pad with hole? howto?
Message-ID:	<20120530004536.GA29981@nome03.eecs.oregonstate.edu>
References:	<20120529223834 DOT GA28710 AT nome03 DOT eecs DOT oregonstate DOT edu>
	<CAN0Jx-97Sr=9tdOZzvMs2kH_=y4sz5oPzyNQWC4_Gd-ZRCX1eA AT mail DOT gmail DOT com>
MIME-Version:	1.0
In-Reply-To:	<CAN0Jx-97Sr=9tdOZzvMs2kH_=y4sz5oPzyNQWC4_Gd-ZRCX1eA@mail.gmail.com>
User-Agent:	Mutt/1.5.20 (2009-12-10)
X-MIME-Autoconverted:	from quoted-printable to 8bit by delorie.com id q4U0jffb031546
Reply-To:	geda-user AT delorie DOT com
Errors-To:	nobody AT delorie DOT com
X-Mailing-List:	geda-user AT delorie DOT com
X-Unsubscribes-To:	listserv AT delorie DOT com

Russell et all,
  Awesome!  I was overthinking it.  Thanks so much.  Here is my work below if
  it is helpful to someone else.
Roger

-----------------------------------------------------------------------------

Element[0x00000000   "" "" "" 10000 10000 -3000 -13000 0 100 0x00000000]
# footprint for Bomar Interconnect SMA edge connector,  part number 961E504
# 3mil soldermask clearence (.076mm)
# 7mil silk outline (.178mm)
# 8mil clearance to any conductor (0.203mm)
(

#        rX1       rY1      rX2      rY2      thick    clear     mask     drill   name   numb  SFlags    NFlags
Pad[   -1.205mm   0.000mm  2.025mm  0.000mm   1.27mm  1.703mm   1.422mm           "sig"   "1"  "square" ]
#top pads
Pin[    0.000mm  -2.500mm                     3.00mm  3.406mm   3.076mm   2.00mm  "gnd"   "2"  "square" ]
Pad[   -0.340mm  -2.500mm  1.160mm -2.500mm   3.00mm  3.406mm   3.152mm           "gnd"   "2"  "square" ]

Pin[    0.000mm   2.500mm                     3.00mm  3.406mm   3.076mm   2.00mm  "gnd"   "3"  "square" ]
Pad[   -0.340mm   2.500mm  1.160mm  2.500mm   3.00mm  3.406mm   3.152mm           "gnd"   "3"  "square" ]

#solderside pads
Pad[   -0.340mm  -2.500mm  1.160mm -2.500mm   3.00mm  3.406mm   3.152mm           "gnd"   "2"  "square,onsolder" ]
Pad[   -0.340mm   2.500mm  1.160mm  2.500mm   3.00mm  3.406mm   3.152mm           "gnd"   "3"  "square,onsolder" ]


#outline, 7mil outline
#top
ElementLine [-2.040mm -4.200mm  2.860mm -4.200mm 0.178mm]
#right
ElementLine [ 2.860mm -4.200mm  2.860mm  4.200mm 0.178mm]
#bottom
ElementLine [ 2.860mm  4.200mm -2.040mm  4.200mm 0.178mm]
#left
ElementLine [-2.040mm  4.200mm -2.040mm -4.200mm 0.178mm]

Attribute("author" "R. Traylor")
Attribute("copyright" "2012 R. Traylor")
Attribute("use-license" "Unlimited")
Attribute("dist-license" "GPL")
)

-----------------------------------------------------------------------------

On Tue, May 29, 2012 at 04:09:27PM -0700, Russell Dill wrote:
> Just put a pad and pin in the same place. Give them both the same name
> and don't forget to put a 'onsolder' pad for the opposite side too.
> 
> On Tue, May 29, 2012 at 3:38 PM, Traylor Roger
> <traylor AT eecs DOT oregonstate DOT edu> wrote:
> > Gang,
> >  I'm trying to use an edge launch SMA connector with snap in terminals
> >  as seen at http://www.bomarinterconnect.com/sma_edgemnt.htm.
> >
> >  I'd like to make the signal return pads rectangular and place the
> >  plated through retention hole in them.
> >
> >  Not finding a way to create a rectangular pad with a plated through
> >  hole. Any ideas?
> >
> >  Thanks,
> >  Roger Traylor

- Raw text -